All Courses
All Courses
Courses by Software
Courses by Semester
Courses by Domain
Tool-focused Courses
Machine learning
POPULAR COURSES
Success Stories
In this project, a simulation of a gate valve will be conducted in ANSYS Fluent using Parameters. A gate valve is a control valve used to control the rate of flow of fluid through a pipe. It is used mostly to shut off flow. It is controlled by turning a handwheel which is connected to a spindle, when the handwheel…
Dushyanth Srinivasan
updated on 05 May 2022
In this project, a simulation of a gate valve will be conducted in ANSYS Fluent using Parameters.
A gate valve is a control valve used to control the rate of flow of fluid through a pipe. It is used mostly to shut off flow. It is controlled by turning a handwheel which is connected to a spindle, when the handwheel is turned, the spindle moves up or down. The spindle is connected to a gate which moves with the spindle when the handwheel is turned.
In this project, a gate valve will be opened from 10% to 80% of the full lift of the gate valve. Each step will increase the opening by 10% or 10mm, and the results will be analysed. The geometry will not be updated for each opening, instead the opening lift value will be parameterised.
Geometry
The geometry was imported into SpaceClaim as a .STEP file. A few operations were performed on the geometry, they are:
Extending outlet and inlet
The outlet face was selected using the pull tool and extended for a length of 800mm. The same was done for the inlet face in the other direction.
Moving the Gate Disk
The gate disk component was selected, it was moved upwards along the Z axis using the move tool, and length of the lift was parameterised by going to Groups -> Create Parameter -> Ruler dimension.
Extraction of Volume
Prepare -> Volume: Select the inlet, outlet and top edge loops and extract the required volume.
The gate valve components can be surpressed for physics.
This is the final geometry in spaceclaim:
Zooming in and hiding the gate valve,
Due to a bug with ANSYS 2022 R1, for each parameter, the geometry module was opened, the extracted volume was updated for the current parameterised geometry.
Note: The gate valve components should be visible but can be supressed when updating the volume.
Meshing
The default meshing method with a mesh size of 50mm was used.
An additional control was introduced to ensure more finer cells are present near the gate valve. It is a sphere of influence having a radius of 30 mm and centered at 0mm, 0mm, 150mm in cartesian coordinates. It is added by going to Mesh -> Controls -> Body Sizing -> Sphere of Influence. Note: This control was only applicable for 10%, 20% and 30% fill as this control proved infeasable beyond that due to restrictions on the ANSYS student license.
This is the final mesh:
Zooming in,
Mesh Metrics
As seen from the metrics, most elements have a quality >=0.75, this implies that the mesh quality is satifactory.
The mesh is dynamically generated for each parameter, hence the number of nodes and elements vary accordingly. An output parameter was created for number of nodes and elements.
Simulation Setup
Solver - General
This simulation ran on a steady state, 3D and with gravity enabled.
Turbulence Model
keps was the preffered turbulence model due to its excellence in this type of flow.
Materials
Water was added from the Fluent database and air was removed.
Properties of water are below:
Density of Air: 998.2kg/m3
Viscosity of Air: 0.001003kg/m.s
Boundaries
inlet: pressure-inlet with a gauge pressure of 10Pa
outlet: pressure-outlet with a gauge pressure of 0Pa
Other boundaries were left untouched
Cell Zone Conditions
The interior volume was set to water-liquid material.
User Defined Field Functions
Two user defined functions were created for the major flow factor and flow coefficient.
Flow Factor
Flow Factor is a measure used to quantify the efficiency at allowing a fluid to pass through it. It is calculated using metric units.
Mathematically,
Kv=Q⋅√SGΔP
Where, Kv is the flow factor (m3/hr), Q is the flowrate (m3/hr), SG is the specific gravity of the fluid and ΔP is the pressure differential (bar).
In this case, Q is calculated from the simulation (m3/s), SG=1, ΔP=10Pa≡0.0001bar.
Simplifying,
Kv=Q⋅√110−4⋅3600
Kv=Qâ‹…100â‹…3600
This simplified formula is created as a custom user defined formula in ANSYS fluent.
Flow Coefficient
Flow Coefficient is a measure used to quantify the efficiency at allowing a fluid to pass through it. It is calculated using American units.
Mathematically,
Cv=Q⋅√SGΔP
Where, Cv is the flow factor, Q is the flowrate (gal/min), SG is the specific gravity of the fluid and ΔP is the pressure differential (ψ).
Instead of calculating all variables in non-metric units, Cv can be found by dividing Kv by 0.865.
Cv=Kv0.865
This simplified formula is created as a custom user defined formula in ANSYS fluent.
Reports
Four reports were generated for each simulation, all report parameters were selected as an output parameter. These reports were monitored during the simulation.
1. Mass Flow at Outlet
2. Volume Flow Rate at outlet
3. Flow Factor
4. Flow Coefficient
Contours
One contour for the velocity across the fluid volume (YZ plane) was created.
The simulation with this setup was performed for different values of opening lift. The simulation was conducted for 250 iterations or until the residuals dropped below a value of 0.0001.
Simulation Results
10mm/10% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
Residuals have droppped below 1e-4 in this case, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
We can notice a high velocity region near the gate, as expected due to compression of flow.
Number of mesh nodes: 35145
Number of mesh elements: 169396
Number of iterations taken for this solution: 62 iterations
Mass flow rate at the outlet: 0.2086 kg/s
Flow Factor at outlet: 15.694 m3/hr
Flow Coefficient at outlet: 18.143 gal/min
20mm/20% opening of gate valve
Residuals
Residuals have not dropped below 1e-4 but they seem to be on a steady path and no further drop is expected, hence we can say the solution has converged. The residuals of turbulence values are ignored as turbulence is not the main focus of this simulation.
Velocity Contour
The increase in velocity near the gate valve is still visible.
Number of mesh nodes: 48281
Number of mesh elements: 241893
Number of iterations taken for this solution: 250 iterations
Mass flow rate at the outlet: 0.3116 kg/s
Flow Factor at outlet: 35.0304 m3/hr
Flow Coefficient at outlet: 40.497 gal/min
30mm/30% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
The residuals have entered a periodic behavior, while the reports generated show a steady-state behaviour, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
The increase in velocity near the gate valve is still visible.
Number of mesh nodes: 81795
Number of mesh elements: 438558
Number of iterations taken for this solution: 300 iterations
Mass flow rate at the outlet: 0.4144 kg/s
Flow Factor at outlet: 61.936 m3/hr
Flow Coefficient at outlet: 71.603 gal/min
40mm/40% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
The residuals have entered an erratic behavior, but the reports generated show a steady-state behaviour, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
The increase in velocity near the gate valve is still visible but the intensity has decreased.
Number of mesh nodes: 28112
Number of mesh elements: 133673
Number of iterations taken for this solution: 202 iterations
Mass flow rate at the outlet: 0.5384 kg/s
Flow Factor at outlet: 104.552 m3/hr
Flow Coefficient at outlet: 120.869 gal/min
50mm/50% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
The residuals seem to be not dropping further, but the reports generated show a steady-state behaviour, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
The increase in velocity is not visible as the velocity has fully dissipated throughout the valve.
Number of mesh nodes: 28074
Number of mesh elements: 133156
Number of iterations taken for this solution: 121 iterations
Mass flow rate at the outlet: 0.6251 kg/s
Flow Factor at outlet: 140.941 m3/hr
Flow Coefficient at outlet: 162.937 gal/min
60mm/60% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
The residuals have entered an erratic behavior, but the reports generated show a steady-state behaviour, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
The increase in velocity is not visible as the velocity has fully dissipated throughout the valve.
Number of mesh nodes: 27761
Number of mesh elements: 130809
Number of iterations taken for this solution: 300 iterations
Mass flow rate at the outlet: 0.6826 kg/s
Flow Factor at outlet: 168.082 m3/hr
Flow Coefficient at outlet: 194.315 gal/min
70mm/70% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
The residuals seem to be not dropping further, but the reports generated show a steady-state behaviour, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
The increase in velocity is not visible as the velocity has fully dissipated throughout the valve.
Number of mesh nodes: 32092
Number of mesh elements: 151663
Number of iterations taken for this solution: 191 iterations
Mass flow rate at the outlet: 0.7487kg/s
Flow Factor at outlet: 202.210 m3/hr
Flow Coefficient at outlet: 233.769 gal/min
80mm/80% opening of gate valve
SpaceClaim Cross-Sectional View
Residuals
This was taken in Fluent.
The residuals seem to be not dropping further, but the reports generated show a steady-state behaviour, hence we can say the solution has converged.
Velocity Contour
This was taken in Fluent.
The increase in velocity is not visible as the velocity has fully dissipated throughout the valve.
Number of mesh nodes: 32163
Number of mesh elements: 152044
Number of iterations taken for this solution: 205 iterations
Mass flow rate at the outlet: 0.786684 kg/s
Flow Factor at outlet: 223.196 m3/hr
Flow Coefficient at outlet: 258.0305 gal/min
General trends observed in the results
Mass Flow Rate
Mass flow rate increases as the gate valve is opened further. Opening the gate valve increases the cross sectional area at the valve and decreases the resitance offered to the fluid flow, hence this behaviour is in agreement with expected results.
Flow Factor and Flow Coefficient
Both of the flow quantities increase as the gate valve is opened further. Opening the gate valve increases the cross sectional area at the valve and decreases the resitance offered to the fluid flow, this increases the efficieny of the flow as seen in these values. Hence, this behaviour is in agreement with expected results.
Summary Table
This table summarises all the numerical results from all the simulations conducted in this project.
Sno. | Lift of Gate Valve (mm) | mass-flow-at-outlet-op (kg/s) | flow-factor (m3/hr) | flow-coefficient (gal/min) | Mesh nodes | Mesh Elements |
1 | 10 | 0.20860554 | 15.694107 | 18.143476 | 35145 | 169396 |
2 | 20 | 0.31165964 | 35.03048 | 40.497664 | 48281 | 241893 |
3 | 30 | 0.41441225 | 61.936989 | 71.603457 | 81795 | 438558 |
4 | 40 | 0.53842437 | 104.55248 | 120.86992 | 28112 | 133673 |
5 | 50 | 0.62513845 | 140.941 | 162.93756 | 28074 | 133156 |
6 | 60 | 0.68268308 | 168.08278 | 194.31536 | 27761 | 130809 |
7 | 70 | 0.748786395 | 202.2108523 | 233.7697689 | 32092 | 151663 |
8 | 80 | 0.786684344 | 223.1964138 | 258.0305334 | 32163 | 152044 |
Conclusions
1. The simulation ran well and expected results were obtained. The mass flow rate does increase with opening %, same behaviour is observed with the flow coefficient and flow factor as well.
2. While the general trend may be visible, the solution often struggles to converge. This could be due to improper mesh settings, and more number of elements are required. (this would violate conditions of the academic license)
3. There are velocity hotspots near the partly closed/opened gate valve, which is expected as flow area contracts. This can be explained by the flow rate formula: Q=V×A. The flow rate (Q) is constant, when the area (A) decreases, to compensate for decrease in area, velocity (V) has to increase.
4. This simulation also shows the advantages of using parameters in ANSYS, and how much time can be saved when conducting nearly similar simulations.
References
https://tameson.com/gate-valve.html
Leave a comment
Thanks for choosing to leave a comment. Please keep in mind that all the comments are moderated as per our comment policy, and your email will not be published for privacy reasons. Please leave a personal & meaningful conversation.
Other comments...
Project 2 - Rankine cycle Simulator
In this project, I will be writing code in MATLAB to simulate a Rankine Cycle for the given parameters. A Rankine Cycle is an ideal thermodynamic heat cycle where mechanical work is extracted from the working fluid as it passes between a heat source and heat sink. This cycle or its derivatives is used in steam engines…
04 Sep 2022 12:52 PM IST
Project 1 - Parsing NASA thermodynamic data
In this project, I will be parsing a data file prepared by NASA. The contents of the data file can be used to generated thermodynamic properties such as Specific Heat at Constant Pressure 'C_p' (J/(kg.K)), Enthalpy HorQ (J) and Entropy S (J/(kg.mol)) at various temperatures. The files will be parsed in MATLAB…
31 Aug 2022 01:07 PM IST
Week 5 - Genetic Algorithm
In this project, I will be generating a stalagmite function in MATLAB and find the global maxima of the function using Genetic Algorithm. A stalagmite function is a function which generates Stalactites, which are named after a natural phenomenon where rocks rise up from the floor of due to accumulation of droppings of…
29 Aug 2022 07:55 AM IST
Week 4.1 - Solving second order ODEs
In this project, I will be writing code in MATLAB to solve the motion of a simple pendulum. A simple pendulum motion's depends on Newton's Second Law. The equation which governs the motion of a simple pendulum is (with damping) d2θdt2+bmdθdt+gLsinθ=0 Where, θ is the angular displacement…
23 Aug 2022 08:06 AM IST
Related Courses
0 Hours of Content
Skill-Lync offers industry relevant advanced engineering courses for engineering students by partnering with industry experts.
© 2025 Skill-Lync Inc. All Rights Reserved.